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Geometry Requirements - Tube Section

The following items are required for a component to be used as a Tube Section in SolidWorks Routing.

Names of routing sketches and dimensions are case sensitive.

Required Items

Examples

PipeSketch

  • A front-oriented sketch named PipeSketch

  • Two concentric circles, centered at the origin of the sketch, with dimensions named:

    • InnerDiameter@PipeSketch

    • OuterDiameter@PipeSketch

  • The inner circle must be defined as For construction

To avoid errors in the sweep feature when creating tube routes, the tube thickness should be no greater than 0.25 times the outer diameter. (That is, make the outer diameter no more than twice the inner diameter.)

Sweep-path sketch

  • In a 3D sketch, a line normal to the PipeSketch

  • A concentric relation between the endpoint of the line and the centerpoint of the circles

 

 

Feature

A Sweep using:

  • PipeSketch for Profile

  • The 3Dsketch for Path

  • The Thin Feature option to set the wall thickness

 

FilterSketch

  • A sketch named FilterSketch

  • A circle with a dimension named NominalDiameter@FilterSketch

 



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