Sketch

When you open a new part document, first you create a sketch. The sketch is the basis for a 3D model. You can create a sketch on any of the default planes (Front Plane, Top Plane, and Right Plane), or a created plane.  You can start by selecting:

• Sketch entity tools (line, circle, and so on)

• Sketch tool

• Planes

• Extruded Boss/Base or Revolved Boss/Base on the Features toolbar .

You can also create a sketch on a flat surface, a spline on a surface, or the face of a solid.

To start a sketch with a sketch entity tool or with the Sketch tool:

1. Click a sketch entity tool (line, circle, and so on) on the Sketch toolbar.

- or -

Click Sketch on the Sketch toolbar, or click Insert, Sketch.

2. Select one of the three planes (Front, Top, and Right) displayed.

3. Create a sketch with the sketch entity tool, or select a tool on the Sketch toolbar and create a sketch.

4. Dimension the sketch entities.

5. Exit the sketch, or click Extruded Boss/Base or Revolved Boss/Base on the Features toolbar.

To start a sketch with a plane:

1. Select a plane in the FeatureManager design tree and click a sketch entity tool or click Sketch on the Sketch toolbar.

In new parts, the plane is displayed in Normal to orientation.

2. Create the sketch, and follow steps 4 and 5 from the previous procedure.

To start a sketch with an Extruded or Revolved Boss/Base:

1. Click Extruded Boss/Base or Revolved Boss/Base on the Features toolbar, or click Insert, Boss/Base, Extrude or Boss/Base, Revolve.

2. Select one of the three planes (Front Plane, Top Plane, and Right Plane) displayed.

In new parts, the plane rotates to the Normal to orientation.

3. Create a sketch with the sketch entity tool, or select a tool on the Sketch toolbar and create a sketch.

The sketch must be a closed sketch.

4. Close the sketch to open the PropertyManager of the feature you selected.

5. Create the part and click OK .

To edit an existing sketch:

• Click Sketch on the Sketch toolbar, or click Insert, Sketch. Select an existing sketch to edit.

- or -

• Right-click a sketch in the FeatureManager design tree, or right-click a sketch entity in the graphics area, and select Edit Sketch.

To create a new sketch in a part with existing sketches:

1. Click a sketch tool on the Sketch toolbar, such as Rectangle .

- or -

Click Sketch on the Sketch toolbar, or click Insert, Sketch.

2. Click a plane, face, or edge to add a new sketch, or click Base/Boss Extrude or Base/Boss Revolve .

3. If you clicked Sketch in step 1, or a feature in step 2, click a tool on the Sketch toolbar to create the sketch.

4. Create the sketch, and dimension the sketch entities.

5. Exit the sketch, or click Extruded Boss/Base or Revolved Boss/Base on the Features toolbar.

You can also create a new sketch by extracting entities from an existing sketch.

Related Topics

Where to Start a Sketch

Sketch Complexity

Sketch Options

Sketch Geometry Status

Using 3D Sketching Tools