Hide Table of Contents

Adding Fittings and Components to Routes

You can:
  • Make fitting to fitting connections, such as:
    • Drag flanges onto elbows, valves, and other fittings.
    • Drag elbows onto flanges, valves, and other fittings.
  • Split a run of pipe by dragging a fitting or a pair of flanges into the pipe.
  • Create branch lines in a pipe by dragging a tee into the pipe.
  • Drag entire assemblies with appropriate references into a pipe. For example, you can drag an assembly consisting of a valve with four flanges into a pipe.
  • Drag a flange, a gasket, and another flange into a route to insert a gasket between flanges.

Contents

Adding a Fitting from the Design Library

To add a fitting from the Design Library folder:

  1. While editing the 3D sketch, drag a fitting from the Design Library folder Task_Pane_Design_Library_Folder.gif and point to the location in the 3D sketch where you want to place the fitting.
  2. Before dropping the fitting:

    • Press Tab to view possible alignments of the fitting.
    • Hold down Shift and press the left and right arrow keys to view possible angular orientations of the fitting. (Specify the rotation increments in Routing Options by setting Component rotation increment (degrees).

  3. When the alignment and orientation are correct, drop the fitting.
  4. Select the desired configuration.

    By default, the list in the Select a Configuration dialog box includes only configurations with the correct diameter. To expand the list to include all the configurations in the part, select List all configurations.

  5. Click OK.

Adding a Fitting from the Routing Menu

To add a fitting from the Routing menu:

  1. While editing the 3D sketch, click Add Fitting Tool_AddFitting_RoutingTools.gif (Routing Tools toolbar) or Routing > Routing Tools > Add Fitting.
  2. Select the fitting from the dialog box, then click Open.

    The pointer changes to fit_align.gif.

  3. Align the fitting:

    1. Right-click to view the possible alignments of the fitting.
    2. When the alignment is correct, left-click.

  4. Select the desired configuration, and click OK.

Changing the Alignment of a Fitting

To change the alignment of a fitting:

  1. Right-click the fitting and select Change Fitting Alignment.
  2. Right-click or press Tab to view the possible alignments of the fitting.
  3. When the alignment is correct, left-click or press Enter.

    When fitting reducers to route segments, CPoint diameters must match. Do not change the fitting alignment of a reducer unless the corresponding CPoint diameters are the same.

Controling the Angular Orientation of a Fitting

To control the angular orientation of a fitting:

  1. While editing the 3D sketch, sketch a construction line starting from a point in the 3D sketch.
  2. Add the fitting to the point in the 3D sketch using one of the previous methods.

    The new fitting is aligned such that its Vertical axis is aligned with the construction line.

Using Add to Route

You can add fittings that are components of the main assembly to a route by right-clicking and selecting Add to Route.

Important: Use Add to Route only for end fittings, not for intermediate fittings.

Adding Isogen Data to Fittings

You can export piping and tubing data as a PCF file, for use in other piping applications such as ISOGEN™.

You can assign the following custom properties to export to the PCF file:

Name Location Description
IsogenSkey (required) Fitting part file, typically as a document property, but can be configuration-specific. The SKEY value in the PCF file. Examples: FLSW, FLWN, TEBX, etc. See your ISOGEN application for more details.
IsogenBom (optional) Fitting part file, typically as a configuration-specific property. Part number (ITEM-CODE) in the PCF file, used for BOM generation in the ISOGEN application. If not found, then the software uses SWBomPartno or the configuration name.
IsogenDescription (optional) Fitting part file, typically as a configuration-specific property. Description (DESCRIPTION) in the PCF file, used for BOM description in the ISOGEN application. If not found, then the software uses SWBomPartno or the configuration name.
IsogenComponentType (optional) Fitting part file, typically as a document property, but can be configuration-specific. The software determines the basic component types (flange, tee, cross, elbow, reducer, eccentric reducer, valve) by analyzing the component features (such as the number of RPoints and CPoints and their associated pipe diameters). This does not accommodate all possible component types, so for any other type of component (such as a union, instrument, or reducing elbow), specify the type using this property.
IsogenAttribute1, IsogenAttribute2, IsogenAttribute3, etc. Route assembly file, as document properties.

These properties are mapped to attributes in the PCF file and can be used to transfer any additional data to the ISOGEN application. The assignment of data to attribute is configured in the ISOGEN application.

You can add these properties as custom properties in the template for route assembly documents so that in the route assembly, you only need to add the values.
You cannot skip a property in the sequence. For example, you cannot create IsogenAttribute1 and IsogenAttribute2, skip IsogenAttribute3, then create IsogenAttribute4. When the software encounters an unused attribute number it will not process any further attributes. (The value of the property can be empty if not used.)

Contents



Provide feedback on this topic

SOLIDWORKS welcomes your feedback concerning the presentation, accuracy, and thoroughness of the documentation. Use the form below to send your comments and suggestions about this topic directly to our documentation team. The documentation team cannot answer technical support questions. Click here for information about technical support.

* Required

 
*Email:  
Subject:   Feedback on Help Topics
Page:   Adding Fittings and Components to Routes
*Comment:  
*   I acknowledge I have read and I hereby accept the privacy policy under which my Personal Data will be used by Dassault Systèmes

Print Topic

Select the scope of content to print:

x

We have detected you are using a browser version older than Internet Explorer 7. For optimized display, we suggest upgrading your browser to Internet Explorer 7 or newer.

 Never show this message again
x

Web Help Content Version: SOLIDWORKS 2013 SP05

To disable Web help from within SOLIDWORKS and use local help instead, click Help > Use SOLIDWORKS Web Help.

To report problems encountered with the Web help interface and search, contact your local support representative. To provide feedback on individual help topics, use the “Feedback on this topic” link on the individual topic page.

10.20.4