Hide Table of Contents

Globally Replacing Failed Mate References

If a mate reference is missing from a component that is used in many places in an assembly, you can replace the missing reference for all instances at the same time.

When you replace the mate reference for one of the many affected mates, a dialog box offers the option to replace it in all other mates with the same missing reference.

For this example, suppose you have an assembly that contains two instances of a knob.

The same cylindrical surface on each knob is used in a concentric mate to a block.

Then suppose that a colleague changes the knob and adds a revolved spline feature to replace the cylindrical surface used in the concentric mates.
Original Knob Modified Knob




Now when you open the assembly, the What's Wrong dialog box informs you that two mates (one for each instance of the knob) are missing a mate entity. The mates are flagged in the FeatureManager design tree.

To globally replace failed mate references:

  1. In the FeatureManager design tree, expand Mates .
  2. Select the first failed mate and click Replace Mate Entities .
  3. In the PropertyManager:
    1. Under Mate Entities, select one of the missing mate entities.
    2. For Replacement Mate Entity , in the graphics area, select another cylindrical feature of the knob.
    3. In the PropertyManager, click .
  4. In the dialog box, click Yes, replace all other missing mate references.
    The missing mate reference is replaced in both mates and the error flags disappear from the FeatureManager design tree.



Provide feedback on this topic

SOLIDWORKS welcomes your feedback concerning the presentation, accuracy, and thoroughness of the documentation. Use the form below to send your comments and suggestions about this topic directly to our documentation team. The documentation team cannot answer technical support questions. Click here for information about technical support.

* Required

 
*Email:  
Subject:   Feedback on Help Topics
Page:   Globally Replacing Failed Mate References
*Comment:  
*   I acknowledge I have read and I hereby accept the privacy policy under which my Personal Data will be used by Dassault Systèmes

Print Topic

Select the scope of content to print:

x

We have detected you are using a browser version older than Internet Explorer 7. For optimized display, we suggest upgrading your browser to Internet Explorer 7 or newer.

 Never show this message again
x

Web Help Content Version: SOLIDWORKS 2016 SP05

To disable Web help from within SOLIDWORKS and use local help instead, click Help > Use SOLIDWORKS Web Help.

To report problems encountered with the Web help interface and search, contact your local support representative. To provide feedback on individual help topics, use the “Feedback on this topic” link on the individual topic page.