On a per-document basis, use the Document Properties -
Weldments page to specify how the weldment software creates cut lists and
configurations.
To open the Document
Properties - Weldments page, click .
Default Behavior
The first time you create a part document, the SOLIDWORKS software
turns on the following Weldment document properties in the part template that is
created:
- Automatically create cut
lists
- Automatically update cut
lists
- Rename cut list folders with
Description property value
If you continue to use this part template, these options are enabled
for all new part documents.
To disable any of these options, clear the option, save the template,
and use the saved template to create new parts.
If you create parts using pre-2015 templates, these options are
turned off.
| Automatically create cut lists |
Enables the Create Cut Lists Automatically
setting on the cut list shortcut menu. This
setting automatically groups similar bodies together within one
cut list folder.
|
| Automatically update cut lists (may affect performance with
many bodies) |
Enables the Update Automatically setting on the
cut list shortcut menu. This setting updates the
model's custom properties and internal supporting data when you
make geometry changes or edits to weldments.
|
| Create
derived configurations |
Creates the derived configuration
Default[As Welded] when
you create a structural member in a part. |
| Assign
configuration Description strings |
Only available when Create derived configurations is
enabled. Adds the As Welded and As
Machined configuration descriptions when you
insert a weldment feature into a new part.
|
| Rename
cut list folders with Description property
value |
Enables the option to rename cut
list folders with the Description property value.
- When you create new parts in SOLIDWORKS
2015 or later:
- With
blank templates, the option is
enabled.
- With existing or saved templates
that were created using SOLIDWORKS 2015, the option
is read
from
those templates.
- When you create new parts in an earlier
version than SOLIDWORKS 2015:
- The option is disabled and you must
manually enable it.
- With
existing or saved templates that were created using
an earlier version than SOLIDWORKS 2015, the option
is disabled. Manually enable it for these files.
|
Bounding Box Properties
You can customize the default description settings of bounding box
properties for new or existing solid and sheet metal cut list bodies.
| Solid
Bodies Description |
Properties for solid bodies
include:
- Plate
(Name)
You can overwrite with another
name for Plate in
the
field.
- SW-Thickness
- SW-Width
- SW-Length
You can change the order of properties by
clicking the drop-down arrows. If you select None for a value, the property
is removed from the text expression.
Select Use default
description to use the text expression as the
default.
|
| Sheet
Metal Bodies Description |
Sheet metal bodies only include a
Sheet (Name) property.
You can overwrite and
enter
another name for Sheet in the
field. Select Use default
description to use the text expression as the
default.
|
| Apply
to |
Select to apply a description to
New bounding boxes or to
Existing and new bounding
boxes. |
Cut list IDs
You can generate cut list IDs or unique reference IDs for each cut
list in a cut list folder based on the cut list attributes.
| Generate Cut list IDs |
Generates
cut
list IDs or unique reference IDs for each cut
list. Each generated cut list ID is added in
the corresponding cut list folder. Unique reference IDs result
in
unique
naming convention of cut
lists. The system
uses the unique reference IDs to index the database.
|
| Structure Cut list IDs, Sheet Metal Cut list IDs, Generic Cut list IDs |
Each type of cut list has a
default ID. You can define different expression values based on the
type of cut list. |