Mate PropertyManager - Standard Tab

You add or edit standard mates on the Standard tab of the Mate PropertyManager.

To open the Mate PropertyManager, do one of the following in an assembly:

  • Add a mate by clicking Mate (Assembly toolbar), or Insert > Mate.
  • Edit a mate by expanding the Mates folder in the FeatureManager design tree. Right-click one or more mates, and select Edit Feature.

Mate Selections

Entities to Mate Specifies the entities that you want to mate.

Use the Alt key to temporarily hide a face when you need to select an obscured face for mates.

When the Optimize component placement when adding mates option is enabled, components are placed in more logical positions on the screen and relative to other components when you create mates. To disable this option, click Tools > Options > System Options > Assemblies and clear the option.
Multiple mate mode Mates multiple components to a common reference in a single operation. The following fields and options appear:
Common reference Specifies the entity that you want to mate to other components.
  Component references Specifies the entities on two or more components to mate to the common reference. A mate is added for each component.
  Create multi-mate folder Groups the resulting mates in a Multi-Mates folder. You can change the common reference, mate type, or distance for all mates in the folder in a single operation. Otherwise, a series of individual mates is added to the model.
  Link dimensions Links the dimensions. The variable name in the Shared Values dialog box is the same as the multi-mate folder name.

Available only for Distance and Angle mates in a multi-mate folder.
You can remove a mate from the multi-mate folder by right-clicking it and clicking Remove from Multi-Mate. You can remove all mates from a multi-mate folder by right-clicking the folder and clicking Dissolve Multi-Mate. The mates appear in the Mates folder, and do not have a multi-mate association with each other.

Mate Type

Only the mates that apply to the current selections are available.

Coincident Positions the selected faces, edges, and planes (in combination with each other or combined with a single vertex) so they share the same infinite plane. Positions two vertices so they touch.
Align axes Fully constrains the component.

Available when applying a coincident mate between origins and coordinate systems.
Parallel Places the selected items at a constant distance apart from each other.
Perpendicular Places the selected items at a 90° angle to each other.
Tangent Places the selected items tangent to each other. At least one selection must be a cylindrical, conical, or spherical face.
Concentric Places the selections so that they share the same centerline.

To prevent rotation in concentric mates, after selecting the mating geometry, select Lock rotation. This option is selected automatically if you have Lock rotation of new concentric mates to Toolbox components selected in the Hole Wizard/Toolbox system options.

If you have components with two holes, you can mate those components even when the holes are not the same distance apart by creating a misaligned mate. Select a misalignment type:
Align this mate Solves the first concentric mate exactly, and applies all the misalignment to the linked concentric mate.
Align Linked mate Solves the linked concentric mate exactly, and applies all the misalignment to the first concentric mate.
Symmetric Applies half of the misalignment to each concentric mate.

Specify the Maximum deviation value if you do not want to use the value defined in the document property. To change the Maximum deviation value, clear the Use Document Property option.

The Result section lists the misaligned mates, where the mates are symmetric misaligned mates or only one of the mates is misaligned.

When using misaligned concentric mates, click Remove link between mates to revert the concentric mate.

The misaligned mates appear in a Misaligned folder under the Mates folder.
Lock Maintains the position and orientation between two components.
Distance Places the selected items with the specified distance between them.
Angle Places the selected items at the specified angle to each other.
  Mate alignment Changes the mate alignment.
Aligned Vectors normal to the selected faces point in the same direction.
Anti-Aligned Vectors normal to the selected faces point in opposite directions.
You can control the value of distance and angle mates in a design table. The column header in the design table uses the syntax dimension@mate_name. For example, D1@Distance1. In the table body cells, enter the value for the dimension. See Dimensions in Configurations.

Mates

Mates contains either all the mates added while the PropertyManager is open or all of the mates that you are editing. When there are multiple mates in the Mates box, you can select a mate to edit.

To edit more than one mate at a time, select multiple mates in the FeatureManager design tree, then right-click and click Edit Feature. All the mates appear in the Mates box.

Options

Add to new folder Places new mates in a folder under the Mates folder in the FeatureManager design tree. When this option is cleared, new mates appear in the Mates folder.
Add to New Folder is not available if you select By Status or Separate Fasteners under Group Mates. To access Group Mates, right-click the Mates folder.
Show popup dialog Shows the Mate pop-up toolbar when you add mates. When this option is cleared, you add mates in the PropertyManager.
Show preview Previews a mate when you make enough selections for a valid mate.
Use for positioning only Moves components to the position defined by the mate, but a mate is not added to the FeatureManager design tree. A mate appears in the Mates box so you can edit and position the components, but the mate does not appear in the FeatureManager design tree when you close the Mate PropertyManager.
Use for positioning only is an alternative to adding many mates, then later deleting those mates in the FeatureManager design tree.
Make first selection transparent Makes the first component that you select transparent to make it easier to select the second component. This option is useful if the second component is behind the first.