Break Corner/Corner-Trim PropertyManager

To open the Break Corner/Corner-Trim PropertyManager:

1. Create a sheet metal part.
2. Do one of the following:
   • Click Break-Corner/Corner-Trim (Sheet Metal toolbar) or click Insert > Sheet Metal > Break Corner.
   • Click Corner-Trim (Sheet Metal toolbar) or click Insert > Sheet Metal > Corner Trim.

Break Corner Options

Use the Break Corner tool with folded sheet metal parts.

In the Break Corner PropertyManager, set the following:

	Corner Edges and/or Flange Faces	Select corner edges or flange faces to break. You can select both simultaneously.
	Collect all corners	(Available in flattened sheet metal parts.) Selects all corners.
	Internal corners only	(Available in flattened sheet metal parts.) Selects only internal corners to break. Selected Cleared
	Break type	Select one of the following: Chamfer Distance Value for the chamfer distance. Fillet Radius Value for the fillet radius.

Relief Options

Use the Corner-Trim tool with flattened sheet metal parts.

In the Corner-Trim PropertyManager, set the following:

	Corner edges	Select corner edges to apply relief cuts.
	Collect all corners	Selects all inside corners.
	Relief type	Select one of the following: Circular Square Bend Waist With Relief set to: Circular or Bend Waist set a value for Radius . Square set a value for Side length .
	Centered on bend lines	Adds corner cuts centered relative to the bend lines with Relief set to Circular or Square. Selected Cleared
	Ratio to thickness	Sets a ratio between the Radius or Side length and the sheet metal thickness. The ratio uses the value you set for the Radius or Side length. Clear Ratio to thickness if you want to change the Radius or Side length.
	Tangent to bend	Adds corner cuts that are tangent to the bend lines when Centered on bend lines is selected.
	Add filleted corners	Adds a fillet with a user-defined Radius to selected Corner edges. For convenience, you can add material when the sheet metal part is flattened.