Note PropertyManager

To open this PropertyManager, do one of the following:

• Click Note (Annotation toolbar), or click Insert > Annotations > Note.
• Select one or more notes.
• Right-click one or more notes (hold down Ctrl while you select a group of notes).

Style

In addition to the functionality described in Style, notes have two types of favorite styles:

Text Format

	Left Align	Aligns the text horizontally.
	Center Align
	Right Align
	Top Align	Aligns the text vertically.
	Middle Align
	Bottom Align
	Fit Text	Click to compress or expand selected text.
	Angle	A positive angle rotates the note counterclockwise.
	Insert Hyperlink	Adds a hyperlink to the note. The entire note becomes a hyperlink. Underlining is not automatic, but you can add it by clearing Use document font and clicking Font.
	Link to Property	Lets you access drawing properties and component properties from any model in the drawing so you can add them to the text string.
	Add Symbol	Lets you access the symbol libraries so you can add symbols to text. Place the pointer in the note text box where you want the symbol to appear, then click Add Symbol.
	Lock/Unlock note	(Available in drawings only.) Fixes the note in place. When you edit the note, you can adjust the bounding box, but you cannot move the note itself.
	Insert Geometric Tolerance	Inserts a geometric tolerance symbol into the note. The Geometric Tolerance PropertyManager and the Properties dialog box open so you can define the symbol.
	Insert Surface Finish Symbol	Inserts a surface finish symbol into the note. The Surface Finish PropertyManager opens so you can define the symbol.
	Insert Datum Feature	Inserts a datum feature symbol into the note. The Datum Feature PropertyManager opens so you can define the symbol. If there is an existing geometric tolerance, surface finish, or datum feature symbol in the drawing, you can click the symbol while you edit the note to insert the symbol in the note. To edit the symbol, you must edit the existing symbol in the drawing sheet. When you edit the existing symbol, all instances of the symbol are updated in the sheet.
	Add Zone	Inserts zone information into the text. In the Add Zone dialog box, select one: Zone Inserts column and row, for example, E2 Zone Column Inserts only column, for example, E Zone Row Inserts only row, for example, 2
	Flag Note Bank	In a drawing with a Flag Note Bank, inserts a flag note into a note.
	Link Table Cell	Links a note to the contents of any BOM or hole table cell.
	Insert DimXpert general profile tolerance	Inserts a general all over profile tolerance feature control frame in a note.
	Manual view label	(For projected, detail, section, aligned section, and auxiliary view labels only.) Overrides the options in Document Properties - View Labels. When selected, you can edit the label text. If you later clear the check box, the label updates according to the corresponding View Label options.
	Use document layout	When cleared, you can add content to the label without the SOLIDWORKS software automatically moving/removing the content the next time you edit Document Properties or there is a rebuild.
	Use document font	Uses the font specified in Document Properties - Notes.
	Font	When Use document font is cleared, click Font to open the Choose Font dialog box. Select a new font style, size, and other text effects.
	All uppercase	Sets the text of the note to display in uppercase. The text appears in uppercase but the actual text value is not converted. If you edit the text value in the Edit in Window dialog box or the Custom page of the Properties dialog box, the text appears as you originally entered it. To toggle the All uppercase setting on or off without opening the PropertyManager, select a note or balloon and click Shift + F3.
	Include prefix, suffix and tolerance of dimensions	When selected, if you insert a dimension into a note, any symbols or tolerances included with the dimension appear in the note. When cleared, the dimension appears in the note, but any symbols or tolerances are omitted.

Block Attribute

You can add attribute names to notes in blocks. Attributes are similar to properties in a part, drawing, or assembly.

The Block Attribute section is available only when editing a note (below, "FW") in a block.

Leader

	Leader	Creates a simple leader from the note to the drawing.
	Multi-jog Leader	Creates a leader from the note to the drawing with one or more bends.
	Spline Leader	(Available in drawings only.) Creates a spline leader from the note to the drawing. To modify the spline leader, select the note and drag the control vertex points.
	VDA Leader	(Available in drawings only.) Used with circular balloons to create VDA balloons, which are frequently used in the German automotive industry.
	No Leader
	Auto Leader	Automatically inserts a leader if you select an entity such as a model or sketch edge.
	Leader Left	Originates from the left of the note.
	Leader Right	Originates from the right of the note.
	Leader Nearest	Originates from the left or right of the note, depending on which is closest.
	Straight Leader
	Bent Leader
	Underlined Leader
	Attach Leader Top	In multiline notes, attaches leader to top of note.
	Attach Leader Center	In multiline notes, attaches leader to center of note.
	Attach Leader Bottom	In multiline notes, attaches leader to bottom of note.
	Attach Leader Nearest	In multiline notes, left leader attaches to the top of note and right leader attaches to the bottom of note.
	Always Attached to Balloon	Sets a balloon's leader to always attach to the balloon.
	Break Around	Sets a balloon's leader to break around quantity.
	To bounding box	Select to position leader with bounding box instead of note content. The leaders associated with the note are vertically aligned based on the size of the bounding box instead of the text.
	Arrow Style	Select an arrowhead style. Smart arrowhead Applies the appropriate arrowhead depending on the detailing standard.
	Apply to all	Select to apply a change to all of the arrowheads of the selected note. If the selected note has multiple leaders, and Auto Leader is not selected, you can use a different arrowhead style for each individual leader.

Leader/Frame Style

Use document display

Select to use the style and thickness configured in Document Properties - Notes. Clear to set leader style or thickness .

Border

Style	Specifies a geometric shape (or None) to enclose the text. You can apply borders to entire notes and portions of notes. For portions of notes, select any portion of the note and select a border. Triangle border style
Size	Specifies Tight Fit to the text, a fixed number of characters, or User Defined (where you can set the size below). If you select Tight Fit, you can add padding to specify an offset between the border and text.
Add to Flag Note Bank	Available in numbered formatted notes. Left-click a flag note number and select Add to Flag Note Bank to add the note to the Flag Note Bank.

Watermark

Available in parts and assemblies when a note on the Notes Area annotation view is displayed as a watermark.

Ordering

Behind geometry The watermark appears obscured by the model.

On top of geometry The watermark appears on top of the model.

Transparency Controls the level of the watermark transparency. This watermark is on top of the geometry with a transparency of 70%.

Flag Note Bank

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Parameters

	X Coordinate	Enter the location for the note center.
	Y Coordinate	Enter the location for the note center.
	Display on the screen	Enter the note position in the graphics area. With Display on the screen, the X and Y coordinates are shown in the graphics area where you can type coordinates. The (0,0) position is the lower left corner of the drawing sheet.

Layer

In drawings with named layers, select a Layer .

Display behind sheet

Available on sheet format. Select to display the annotation note on the sheet format behind drawing objects.