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Merging Sheet Metal Bodies by Inserting Edge Flanges

The new Up to Edge and Merge option in the Edge Flange Property Manager connects two parallel edges in a multibody part. The edges must be the same thickness, part of the sheet metal part base, and must belong to different bodies. The option is available if you select a single edge under Flange Parameters.

The Up to Edge and Merge option calculates the angle between the edges automatically. You can unlock the angle to override the calculation to extend or shorten the connecting flange.

To merge the sheet metal bodies in corner_multipart.sldprt:

  1. Click Edge Flange (Sheet Metal toolbar).
  2. In the Edge-Flange PropertyManager, under Flange Parameters, for Edge, select the outside front edge of corner Features1.

  3. Under Flange Length, from the Length End Condition list, select Up to Edge and Merge.
  4. For the reference edge , select the outside front edge of corner_mirrored Features1.
    You must select corresponding edges (for example, the outer edges) on both bodies for Flatten to work. To make selection easier, move over an edge and press G to magnify the area.

  5. Under Flange Position, click Bend Outside .
  6. Click .

    The edge flange merges the two bodies.

    In the FeatureManager design tree Cut List, there is now only one body, Edge-Flange6.

  7. Right-click Edge-Flange6 and click Flatten .

    The merged part flattens.

  8. In the Confirmation Corner, click Exit Flatten to restore the body to its folded state.


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10.20.6