In a section view in a part or assembly document, the model is displayed as if cut by planes and faces that you specify, to show the internal construction of the model.
You can:
- Select bodies or components to include in or exclude from section views.
- Toggle the view off and on. The section view state is retained, even when you save and reopen te document.
- Show or hide a section cap. If you show a section cap, you can choose whether it displays with its own color.
- Select the faces, edges, and vertices created by a section view.
- Save the section view as a named view in the part or assembly document or as an annotation view for use in drawing documents.
You can also create section views in drawings.
Zebra stripes are not available with an active section view.
To create a section view:
- In a part or assembly document, click Section View
(View toolbar) or .
- In the Section View PropertyManager, under Section 1, set the properties.
- To section the model with additional planes or faces, select Section 2 and Section 3 and set the properties.
Section 3 is unavailable until Section 2 has been selected.
- Click Selected bodies or Selected components to create a section view of a part or an assembly, respectively.
- Under Selected components, select one of the following:
| Option |
Description |
|---|
| Exclude selected |
The selected bodies or components are not sectioned. All other bodies or components are sectioned. |
| Include selected |
The selected bodies or components are sectioned. Other bodies or components are not sectioned. |
- Select Enable selection plane.
A selection plane appears to help you select components that are not visible in the model or in the sectioned area. The triad, in the center of the selection plane, controls the position and angle of the selection plane.
- Drag the center ball of the triad to view hidden components.
- Click Preview to show the graphics-only preview of the section based on the section plane location and the components or bodies that you select.
Preview hides the section plane, reference plane and face outlines, and the selection plane.
- Click
.To return the model to full view, click
Section View again.
To edit the section view, right-click in the graphics area and select Section View Properties.