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DimXpert Value PropertyManager

In the DimXpert Value PropertyManager, you specify the display of dimensions and tolerances.

To set the default tolerance and precision values:

Click Options Tool_Options_Standard.gif > Document Properties > DimXpert.

Reference Features

DimXPM_RefFea.gif
PM_Tol_Fea_DimXpert.gif Tolerance Feature The top plane P2.
For size dimensions, only Tolerance Feature PM_Tol_Fea_DimXpert.gif appears in the PropertyManager.
PM_Origin_Fea_DimXpert.gif Origin Feature The bottom plane P1.
See ASME Y14.5M -1994, Paragraph 2.6.1 or ISO 129 for information regarding origin and toleranced features.
PM_Swap_Fea_DimXpert.gif Swap Features
  Examples Using Different Origin Features:
Origin Feature PM_Origin_Fea_DimXpert.gif = the bottom plane P1. Origin Feature PM_Origin_Fea_DimXpert.gif = the top plane P2.
DimX_OrigBot.gif DimX_OrigTop.gif
The origin symbol, in place of the arrowhead, denotes the origin feature.
DimX_OrigBotDims.gif DimX_OrigTopDims.gif
Note the different dimension results.

DimXpert Direction

This option appears when you apply a dimension between two axis- or line-type features. The X, Y, and Z options are relative to the part coordinate system and are enabled for each part axis that is perpendicular to the axes of the features.
The axis of the features is along Z, which enables the X and Y options. DimXPM_DirX.gif
The normal option N orients the dimension along the direction defined by the shortest distance between the two features. DimXPM_DirN.gif
The user-defined option U orients the dimension along a direction parallel to an edge or normal to a planar face.

In this example, the dimension is oriented parallel to an edge.

DimXPM_DirU.gif

Style

See Style for details.

Tolerance/Precision

  Callout value For hole type callouts with multiple specifications, all dimensions are listed individually. This functionality is valid for simple holes with depth, counterbore holes, countersink holes, combined slot dimensions, and chamfers.
PM_tolerance_type_dim.gif Tolerance Type Select from the list. Selections available depend on the type of dimension.
PM_max_variation_dim.gif Maximum Variation  
PM_min_variation_dim.gif Minimum Variation  
  Show parentheses Inserts parentheses around the tolerance value.
dim_unit_prec.png Unit Precision Select the number of digits after the decimal point from the list for the dimension value.
PM_dim_precision_tol.gif Tolerance Precision Select the number of digits after the decimal point for tolerance values.
For Holes and Shafts:    
PM_dim_tol_fit_class.gif Classification (Fit, Fit with tolerance, or Fit (tolerance only)) When you select either Hole Fit or Shaft Fit (below), the list for the other category (Hole Fit or Shaft Fit) is filtered based on the classification.
PM_dim_tol_hole.gif PM_dim_tol_shaft.gif Hole Fit and Shaft Fit (Fit, Fit with tolerance, or Fit (tolerance only)) Select from the lists, or type any text.
Bilateral tolerances (Maximum Variation and Minimum Variation) are available in the Fit with tolerance or Fit (tolerance only) type if you specify Hole Fit or Shaft Fit, but not both.
  Fit tolerance display (Fit, Fit with tolerance, or Fit (tolerance only)) Select one of the following:

Stacked with line display PM_dim_tol_fit_withline.gif

Stacked without line display PM_dim_tol_fit_stacked.gif

Linear display PM_dim_tol_fit_linear.gif

Primary Value

This option is read-only. It displays the dimension name and value.

Dimension Text

  Instance Count For patterns, this shows the number of instances.
PM_AddParenthesis.gif Add Parentheses You can display driven (reference) dimensions with or without parentheses. They are displayed with parentheses by default.
dimension_dimx_parentheses.gif
PM_CenterDim.gif Center Dimension When you drag dimension text between the extension lines, the dimension text snaps between the center of the extension lines.
dimension_center.gif
PM_InspectionDim.gif Inspection Dimension Dimension_Inspection.gif
PM_OffsetText.gif Offset Text Offsets dimension text from the dimension line using a leader.
dimension_offset_text.gif
  Text The dimension appears automatically in the center text box, represented by <DIM>. Place the pointer anywhere in the text box to insert text.
Holes use the format specified in the txcalloutformat.txt file. See DimXpert Size Dimension, Callout format file, for more information.
  Justify You can justify text horizontally and, for some standards, you can justify the leader vertically.
  • Left Justify justify_left.png Button, Center Justify justify_center.png Button, Right Justify justify_right.png Button.
  • Top Justify PM_dim_Justify_Top.gif, Middle Justify PM_dim_Justify_Middle.gif, Bottom Justify PM_dim_Justify_Bottom.gif.
  Symbols Click to place the pointer where you want a symbol. Click a symbol icon or click More to access the Symbol Library.
Use caution when adding symbols to DimXpert dimensions because the symbols may change the fundamental definition of the dimensions and tolerances.

Dual Dimension

Specifies that the dimension is displayed in both the document's unit system and the dual dimension units. Both units are specified in Tools > Options > Document Properties > Units.
DimX_DualDim.gif

dim_unit_prec.png Unit Precision Select the number of digits after the decimal point from the list for the dimension value.
PM_Tol_Precision_DualDim.gif Tolerance Precision Select the number of digits after the decimal point for tolerance values.


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