The Simple Hole PropertyManager appears when you create a new Simple Hole in a part, or when you edit an existing simple hole feature.
To open this PropertyManager:
Click Simple Hole 
(Features toolbar) or .
From
Sets the starting condition for the simple hole feature.
| Sketch Plane |
Starts the simple hole from the same plane on which the sketch is located. |
| Surface/Face/Plane |
Starts the simple hole from one of these entities. Select a valid entity for Surface/Face/Plane
 . |
| Vertex |
Starts the simple hole from the vertex you select for Vertex  .
|
| Offset |
Starts the simple hole on an plane that is offset from the current sketch plane. Set the offset distance for Enter Offset Value. |
Direction 1
Some fields that accept numeric input allow you to create an equation by entering = ( equal sign) and selecting global variables, functions, and file properties from a drop-down list. See Direct Input of Equations in PropertyManagers.
| |
End Condition |
Select from the available end condition types.
|
 |
Direction of Extrusion |
Extrudes the hole in a direction other than normal to the profile of the sketch. Select any of the following: |
| |
|
- Cylindrical faces
- Conical faces
- Planar faces
- Sketch points
- Vertices
|
- Linear edges
- Linear sketch entities
- Reference axes
- Reference planes
- Points in reference geometry
|
| |
|
 Normal to sketch extrusion
|
 Direction vector extrusion
|
|
Face/Plane |
Select a face or plane in the graphics area to set the hole depth when you choose Up To Surface or Offset From Surface as the End Condition.
|
 |
Offset Distance |
Set the hole depth or offset distance when you choose Blind or Offset From Surface as the End Condition.
Optionally, select the following:
|
Reverse offset
|
Applies the specified Offset Distance in the opposite direction from the selected Face/Plane .
|
|
Translate surface
|
Applies the specified Offset Distance relative to the selected surface or plane. To use a true offset, clear Translate surface.
|
|
| |
|
 True offset - Translate surface check box cleared
|
 Translated surface - Translate surface check box selected
|
|
Vertex |
Select a vertex or midpoint in the graphics area to set the hole depth when you select Up To Vertex as the End Condition.
|
 |
Hole Diameter |
|
 |
Draft On/Off |
Adds draft to the hole. Set Draft Angle to specify the degrees for the draft. Optionally, select the following:
|
Draft Outward
|
Creates an outward draft angle when you select Draft On/Off .
|
|