Revolve PropertyManager

The Revolve PropertyManager appears when you create a new revolve feature, or when you edit an existing revolve feature.

You can specify separate end conditions for each direction (clockwise and counter-clockwise from the sketch plane). The PropertyManager controls the following properties:

Axis of Revolution

• Axis of Revolution . Select an axis around which the feature revolves. This can be a centerline, line, or an edge, depending on the type of revolve feature you create.

Direction1

Defines the revolve feature in one direction from the sketch plane.

• Revolve Type. Sets the end condition of the revolve feature relative to the sketch plane. Click Reverse Direction , if necessary, to reverse the revolve direction. Select one of these options:

• • Blind. Creates the revolve in one direction from the sketch. Set the angle covered by the revolve in Direction 1 Angle .

  • Up to Vertex. Creates the revolve from the sketch plane to the vertex you specify in Vertex .

  • Up to Surface. Creates the revolve from the sketch plane to the surface you specify in Face/Plane .

  • Offset from Surface. Creates the revolve from the sketch plane to a specified offset from the surface you specify in Face/Plane . Set the offset in Offset Distance . If necessary, select Reverse offset to offset in the opposite direction.

  • Mid-Plane. Creates the revolve in the clockwise and counter-clockwise directions from the sketch plane, which is located at the middle of the revolve Direction 1 Angle .

• Merge result. (Boss/Base revolves only). Merges resultant body into an existing body if possible. If not selected, the feature creates a distinct solid body.

Direction2

(Optional.) After completing Direction1, select Direction2 to define the revolve feature in the other direction from the sketch plane.

• Revolve Type. Sets the end condition of the revolve feature relative to the sketch plane. Click Reverse Direction , if necessary, to reverse the revolve direction. Select one of these options:

• • Blind. Creates the revolve in one direction from the sketch. Set the angle covered by the revolve in Direction 2 Angle .

  • Up to Vertex. Creates the revolve from the sketch plane to the vertex you specify in Vertex .

  • Up to Surface. Creates the revolve from the sketch plane to the surface you specify in Face/Plane .

  • Offset from Surface. Creates the revolve from the sketch plane to a specified offset from the surface you specify in Face/Plane . Set the offset in Offset Distance . If necessary, select Reverse offset to offset in the opposite direction.

Thin Feature

Select Thin Feature and set these options:

• Type. Defines the direction of thickness. Select one of these options:

• • One-Direction. Adds the thin-walled volume in one direction from the sketch. Click Reverse Direction , if necessary, to reverse the direction in which the thin-walled volume is added.

  • Mid-Plane. Adds the thin-walled volume using the sketch as the middle, and applying thin-walled volume equally on both sides of the sketch.

  • Two-Direction. Adds the thin-walled volume on both sides of the sketch. Direction 1 Thickness adds thin-walled volume outward from the sketch. Direction 2 Thickness adds thin-walled volume inward from the sketch.

• Direction 1 Thickness . Sets the thin-walled volume thickness for One-Direction and Mid-Plane thin feature revolves.

Selected Contours

Use this option when you create a revolve using multiple contours.

• Selected Contours . Select contours in the graphics area to create the revolve, as follows:

The region changes color.

The region of the sketch appears in the Selected Contours box. You can select any combination of regions to create single or multibody parts.

3. Click .

Feature Scope

Specifies which bodies or components you want the feature to affect.

• For multibody parts, see Feature Scope in Multibody Parts.

• For assemblies, see Feature Scope in Assemblies.

Related Topics

Revolve Features

Revolved Surface