Hide Table of Contents

Varying the Spacing and Dimensions of All Instances

The seed feature in this pattern is a cut extrude with a fillet. In this task, you use the Instances to Vary options to vary the spacing and dimensions of all instances in the pattern.

  1. Open the model install_dir\samples\whatsnew\parts\simple_plate.sldprt.

    wn2013_varydims

  2. In the FeatureManager design tree, select Lpattern and right-click Edit Feature fm_edit_feature.gif.

    The LinearPattern PropertyManager appears.

  3. In the PropertyManager, click Instances to Vary.
  4. In the graphics area, click the height (8) and width (6) dimensions of the seed feature.

    wn2013_varydims_1

    The Instances to Vary box populates a table with the dimensions and values.

  5. Under Direction 1 Increments:
    1. Set Spacing PM_space_increment to 5mm.
    2. For the Height dimension, set Increment to 10mm.
  6. Click PM_OK.gif.

The spacing between all the instances increase by 5mm.

Each instance increases in height by 10mm over the preceding instance. For example, since the height of the seed instance is 8mm, the height of succeeding instances increase to 18mm, 28mm, 38mm and 48mm.

wn2013_varydims_3



Provide feedback on this topic

SOLIDWORKS welcomes your feedback concerning the presentation, accuracy, and thoroughness of the documentation. Use the form below to send your comments and suggestions about this topic directly to our documentation team. The documentation team cannot answer technical support questions. Click here for information about technical support.

* Required

 
*Email:  
Subject:   Feedback on Help Topics
Page:   Varying the Spacing and Dimensions of All Instances
*Comment:  
*   I acknowledge I have read and I hereby accept the privacy policy under which my Personal Data will be used by Dassault Systèmes

Print Topic

Select the scope of content to print:

x

We have detected you are using a browser version older than Internet Explorer 7. For optimized display, we suggest upgrading your browser to Internet Explorer 7 or newer.

 Never show this message again
x

Web Help Content Version: 2013 SP05

To disable Web help from within SOLIDWORKS and use local help instead, click Help > Use SOLIDWORKS Web Help.

To report problems encountered with the Web help interface and search, contact your local support representative. To provide feedback on individual help topics, use the “Feedback on this topic” link on the individual topic page.

0.20.26