Convert Entities
You can create one or more curves in a sketch by projecting an edge, loop, face, curve, or external sketch contour, set of edges, or set of sketch curves onto the sketch plane.
To convert an entity:
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In an open sketch, click a model edge, loop, face, curve, external sketch contour, set of edges, or set of curves.
You can also click an entity after clicking the Convert Entities 
tool.
Examples:
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Select a face to convert the edges of the face.
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Select a face, then press Ctrl and select an edge of a loop. The software selects only the loop.
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Select contiguous faces to get an entire outline of the faces. The line segments correspond to each face.
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Click Convert Entities (Sketch toolbar) or Tools, Sketch Tools, Convert Entities.
The following relations are created:
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On Edge 
. Created between the new sketch curve and the entity, which causes the curve to update if the entity changes.
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Fixed. Created internally on the endpoints of the sketch entity so the sketch remains in a "fully defined" state. This internal relation is not displayed when you use Display/Delete Relations. Remove the Fixed relation by dragging the endpoints.
If you are creating a component or feature
in the context of an assembly
and Do not create references external to the model is selected in Tools, Options,
External References
, then the sketch relations described above are not created. See
Controlling Creation of External References
.
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In the PropertyManager, click Select chain to convert all contiguous sketch entities.
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Click 
.
Related Topics
Offset Entities
Silhouettes