Sketch Relations in Configurations
You can control the suppression state of sketch relations per configuration.
To suppress or unsuppress sketch relations:
-
Right-click a sketch in the FeatureManager design tree, and select Edit Sketch.
-
Click Display/Delete Relations 
on the Dimensions/Relations toolbar.
-
In the PropertyManager, under Configurations (at the bottom of the PropertyManager), select the configurations to which you want the sketch relations to apply:
,
, or
(these options are only available if there is more than one configuration in the model).
NOTES:
-
You must select a configuration prior to changing sketch relations. When you change sketch relations, the change is immediately applied to the selected configuration.
-
If you selected Specify configurations, you cannot clear the active configuration.
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Under Relations, select the sketch relations to suppress or unsuppress.
-
Select or clear Suppressed.
When Suppressed is selected, the sketch relation's Information Status 
changes from Satisfied to Driven.
-
Click OK 
, and exit the sketch.
The sketch relation is applied to the selected configurations.
To suppress or unsuppress sketch relations in a design table:
The column header in a design table for controlling sketch relations uses this syntax:
$STATE@<sketch_relation>@<sketch_name>
For example, to control the suppression state of the first fixed relation in Sketch2, the column heading syntax is $STATE@Fixed1@Sketch2.
The column header is not case sensitive.
In the table body cells, type S for suppressed or U for unsuppressed.
Sketch relations and sketch entities include an assigned number (such as Fixed1) in the
Display/Delete Relations
PropertyManager.
Example of a design table that controls the suppression state of a sketch relation:
